Sample Programs

Classic Control - Lathe Operator's Manual

The Online Interactive Operator's Manual is currently available in English only.

A PDF version of the Operator's Manual is available for download in multiple languages. Click the link below to view the Operator's Manual in your language. Click "Continue" to view the online version in English.

Get a translated PDF Download Continue

Cartesian Interpolation Example 1. (1) Projected Cutting Path (A) The endmill feeds 1" into the workpiece on one side. (B) The C Axis turns 180 degrees to cut the arc shape. (C) The endmill feeds 1" out of the workpiece.

% o51121 (CARTESIAN INTERPOLATION EX 1) ; (G54 X0 Y0 is at the center of rotation) ; (Z0 is on face of the part) ; (T1 is an end mill) ; (BEGIN PREPARATION BLOCKS) ; T101 (Select tool and offset 1) ; G00 G18 G20 G40 G80 G99 (Safe startup) ; G98 (Feed per min) ; M154 (Engage C Axis) ; G00 G54 X2. C90 Z0.1 (Rapid to 1st position) ; P1500 M133 (Live tool CW at 1500 RPM) ; M08 (Coolant on) ; (BEGIN CUTTING BLOCKS) ; G01 Z-0.1 F6.0 (Feed to Z depth) ; X1.0 (Feed to Position 2) ; C180. F10.0 (Rotate to cut arc) ; X2.0 (Feed back to Position 1 ) ; (BEGIN COMPLETION BLOCKS) ; G00 Z0.5 M09 (Rapid retract, coolant off) ; M155 (Disengage C axis) ; M135 (Live tool off) ; G18 (Return to XZ plane) ; G53 X0 Y0 (X & Y home) ; G53 Z0 (Z home) ; M30 (End program) ; %

Cartesian Interpolation Example 2

% o51122 (CARTESIAN INTERPOLATION EX 2); (G54 X0 Y0 is at the center of rotation) ; (Z0 is on face of the part) ; (T1 is a drill) ; (BEGIN PREPARATION BLOCKS) ; T101 (Select tool and offset 1) ; G00 G18 G20 G40 G80 G99 (Safe startup) ; G19 (Call YZ plane) ; G98 (Feed per min) ; M154 (Engage C-Axis) ; G00 G54 X3.25 C0. Y0. Z0.25 ; (Rapid to 1st position) ; P1500 M133 (Live tool CW at 1500 RPM) ; M08 (Coolant on) ; G00 Z-0.75 (Rapid to Z depth) ; (BEGIN CUTTING BLOCKS) ; G75 X1.5 I0.25 F6. (Begin G75 on 1st hole) ; G00 C180. (Rotate C axis to new position) ; G75 X1.5 I0.25 F6. (Begin G75 on 2nd hole) ; G00 C270. (Rotate C axis to new position) ; G75 X1.5 I0.25 F6. (Begin G75 on 3rd hole) ; (BEGIN COMPLETION BLOCKS) ; G00 Z0.25 M09 (Rapid retract, coolant off) ; M155 (Disengage C axis) ; M135 (Live tool off) ; G18 (Return to XZ plane) ; G53 X0 (X home) ; G53 Z0 (Z home) ; M30 (End program) ; %

Be aware: Many service and repair procedures should be done only by authorized personnel. The service technicians at your Haas Factory Outlet (HFO) have the training, experience, and are certified to do these tasks safely and correctly. You should not do machine repair or service procedures unless you are qualified and knowledgeable about the processes.

Danger: Some service procedures can be dangerous or life-threatening. DO NOT attempt a procedure that you do not completely understand. Contact your Haas Factory Outlet (HFO) and schedule a service technician visit if you have any doubts about doing a procedure.

Feedback