Mill - Probing with VQC Templates

Introduction

This document tells you how to use a VQC template to program a Renishaw probe in a mill. It tells you how to:
  • - Load VQC probing templates
  • - Calibrate a probe
  • - Use work offset templates
  • - Find more information


Loading VQC Probing Templates

To select a VQC template:

Press MDI/DNC.

Press PRGRM/CONVRS.

Go to the VQC tab.

Select the Probe Template (O09996).


 

Set Calibration

Press the Down cursor arrow to go to Probe Calibration.

There are three templates:

  • Calibrate OTS Length and Diameter
  • Spindle Probe Z Calibration off OTS
  • Spindle Probe X,Y Calibration

Press WRITE/ENTER to select Calibrate OTS Length and Diameter.

OTS Probe Calibration

Put a gage pin of a known length and diameter in the spindle.

Jog the spindle to the center of the OTS probe, 0.4" (10 mm) above the OTS stylus.

Type the tool length and tool diameter.

Enter -2 if the OTS is set up on the left side of the table, or 2 if it is set up on the right side.

Press WRITE/ENTER.

Select Option 3, Output to MDI.

The G-code program generated during the calibration setup is output to MDI.

Run the program.

OSI Probe Calibration

Use the Right cursor arrow to go to the second calibration option, Spindle Probe Z Calibration off OTS.

Press WRITE/ENTER.

Mount an OMI40-2 probe in the spindle.

Jog the Z Axis in the negative (-) direction until the OMI40-2 is just above the OTS.

Type the tool pocket number of the tool pocket that has the OMP40-2 probe.

Press WRITE/ENTER.

Select Option 3, Output to MDI.

The G-code program generated during the calibration setup is output to MDI.

Run the program.

Press the Right cursor arrow to go to the third calibration option, Spindle Probe X,Y Calibration.

Stylus Diameter Calibration

Mount a ring gauge to the table.

Jog the OMP40 probe stylus to the approximate center of the gauge.

Put the probe tip slightly below the top surface of the gauge.

Type the internal diameter of the ring gauge.

Press WRITE/ENTER

Select Option 3, Output to MDI.

The G-code program generated during the calibration setup is output to MDI.

Run the program.

Work Offset Templates

Work Offset Probe Cycle Examples

1 - Boss

2 - External corner

3 - Web

4 - Pocket

5 - Internal corner

Spindle Probe 1-9

Templates under the Spindle Probe 1-9 heading are:

  • Probe Bore
  • X Plus Surface
  • X Minus Surface
  • Y Plus Surface
  • Y Minus Surface
  • Z Surface
  • Vise (or part) Corner.

Probe Bore Template

Open the Probe Bore template.

This program measures the diameter and position of a bore. It updates the work offset with the bore center-point.

Put the G-code for the work offset in the Wrkofset field. Do not type the G, just the number. For example, to use work coordinate position G54, type in 54. To use work coordinate position G154 P22, type 154.22.

Type in the diameter of the bore.

Output the program to MDI.

 Run the program.

Spindle Probe 10-18

Templates under the Spindle Probe 10-18 heading are:

  • Probe Boss
  • Probe X Pocket
  • Probe Y Pocket
  • Probe X Web
  • Probe Y Web
  • External corner
  • Internal Corner.

Probe Boss Template

Open the Probe Boss template.

This program is similar to the Probe Bore program, but has the added input of the Z Depth (a negative value to put the probe tip below the surface of the part).

Tool Setting Heading

Go back to the VQC tab.

Press the Right cursor arrow until Auto Length Only Sequential Tools is highlighted.

Press WRITE/ENTER.

Auto Length Only, Sequential Tools

The comments means that this template should only be used for tools whose length can be accurately measured on the 0.5" (12 mm) OTS sensor stylus disk. It can not be used for larger tools, such as a 2" (50 mm) fluted end mill.

More Information

Renishaw.com

The Haas visual quick-code probing system (VQCPS) offers a simple way to create and run some basic probing cycles.

VQCPS uses Renishaw's Inspection Plus macro programs.

The Renishaw macros offer advanced inspection and probing cycles.

Visit www.Renishaw.com for more information on how to use the macros offered in Inspection Plus.

Be aware: Many service and repair procedures should be done only by authorized personnel. The service technicians at your Haas Factory Outlet (HFO) have the training, experience, and are certified to do these tasks safely and correctly. You should not do machine repair or service procedures unless you are qualified and knowledgeable about the processes.

Danger: Some service procedures can be dangerous or life-threatening. DO NOT attempt a procedure that you do not completely understand. Contact your Haas Factory Outlet (HFO) and schedule a service technician visit if you have any doubts about doing a procedure.

Feedback