G195/G196 Forward/Reverse Live Tool Radial Tapping (Diameter) (Group 00)

Classic Control - Lathe Operator's Manual

The Online Interactive Operator's Manual is currently available in English only.

A PDF version of the Operator's Manual is available for download in multiple languages. Click the link below to view the Operator's Manual in your language. Click "Continue" to view the online version in English.

Get a translated PDF Download Continue
F - Feed Rate per revolution (G99)
U - X-Axis incremental distance
S - RPM, called prior to G195
X - Position of the X Axis at the bottom of hole
Z - Z-Axis position before drilling

The tool must be positioned to the start point before commanding G195/G196. This G code is called for each hole being tapped. The cycle begins from the current position, tapping to the X-axis depth specified. An R plane is not used. Only X and F values should be used on G195/G196 lines. The tool must be positioned to the start point of any additional holes before commanding G195/G196 again.

S RPM should be called out as a positive number. It is not necessary to start the spindle in the correct direction; the control does this automatically.

G195/G196 Live Tooling Rigid Tapping: [1] Rapid, [2] Feed, [3] Start or end of stroke, [4] Starting point, [5] Part surface, [6] Bottom of the hole, [7] Centerline.

% o61951 (G195 LIVE RADIAL TAPPING) ; (G54 X0 Y0 is at the center of rotation) ; (Z0 is on the face of the part) ; (T1 is a tap) ; (BEGIN PREPARATION BLOCKS) ; T101 (Select tool and offset 1) ; G00 G18 G20 G40 G80 G99 (Safe startup) ; M154 (Engage C Axis) ; G00 G54 X3.25 Z-0.75 C0. (Start Point) ; M08 (coolant on) ; (BEGIN CUTTING BLOCK) ; S500 (Select tap RPM) ; G195 X2. F0.05 (Taps to X2., bottom of hole) ; G00 C180. (Index C-Axis. New Start Point) ; G195 X2. F0.05 (Taps to X2., bottom of hole) ; G00 C270. Y-1. Z-1. ; (Optional YZ-axis positioning, new start point) ; G195 X2. F0.05 (Taps to X2., bottom of part) ; (BEGIN COMPLETION BLOCKS) ; G00 Z0.25 M09 (Rapid retract, coolant off) ; M155 (Disengage C Axis) ; G53 X0 Y0 (X & Y home) ; G53 Z0 (Z home) ; M30 (End program) ; %

Be aware: Many service and repair procedures should be done only by authorized personnel. The service technicians at your Haas Factory Outlet (HFO) have the training, experience, and are certified to do these tasks safely and correctly. You should not do machine repair or service procedures unless you are qualified and knowledgeable about the processes.

Danger: Some service procedures can be dangerous or life-threatening. DO NOT attempt a procedure that you do not completely understand. Contact your Haas Factory Outlet (HFO) and schedule a service technician visit if you have any doubts about doing a procedure.

Feedback