G10 Set Offsets (Group 00)

Next Generation Control Mill Operator's Manual

The Online Interactive Operator's Manual is currently available in English only.

A PDF version of the Operator's Manual is available for download in multiple languages. Click the link below to view the Operator's Manual in your language. Click "Continue" to view the online version in English.

Get a translated PDF Download Continue

G10 lets you set offsets within the program. G10 replaces manual offset entry (i.e. Tool length and diameter, and work coordinate offsets).

L – Selects offset category.
L2 Work coordinate origin for G52 and G54-G59
L10 Length offset amount (for H code)
L1 or L11 Tool wear offset amount (for H code)
L12 Diameter offset amount (for D code)
L13 Diameter wear offset amount (for D code)
L20 Auxiliary work coordinate origin for G110-G129
P – Selects a specific offset.
P1-P200 Used to reference D or H code offsets (L10-L13)
P0 G52 references work coordinate (L2)
P1-P6 G54-G59 references work coordinates (L2)
P1-P20 G110-G129 references auxiliary coordinates (L20)
P1-P99 G154 reference auxiliary coordinate (L20)
*R Offset value or increment for length and diameter.
*X X-Axis zero location.
*Y Y-Axis zero location.
*Z Z-Axis zero location.
*A A-Axis zero location.
*B B-Axis zero location.
*C C-Axis zero location.

*indicates optional

% O60100 (G10 SET OFFSETS) ; G10 L2 P1 G91 X6.0 ; (Move coordinate G54 6.0 to the right) ; ; G10 L20 P2 G90 X10. Y8. ; (Set work coordinate G111 to X10.0 Y8.0) ; ; G10 L10 G90 P5 R2.5 ; (Set offset for Tool #5 to 2.5) ; ; G10 L12 G90 P5 R.375 ; (Set diameter for Tool #5 to .375”) ; ; G10 L20 P50 G90 X10. Y20. ; (Set work coordinate G154 P50 to X10. Y20.) ; %

G10 lets you set offsets within the program. G10 replaces manual offset entry (i.e. Tool length and diameter, and work coordinate offsets).

L - Selects offset category.
  • L2 Work coordinate origin for COMMON and G54-G59

  • L10 Geometry or shift offset

  • L1 or L11 Tool wear

  • L20 Auxiliary work coordinate origin for G110-G129

P - Selects a specific offset.
  • P1-P50 - References geometry, wear or work offsets (L10-L11)

  • P51-P100 - References shift offsets (YASNAC) (L10-L11)

  • P0 - References COMMON work coordinate offset (L2)

  • P1-P6 - G54-G59 references work coordinates (L2)

  • P1-P20 G110-G129 references auxiliary coordinates (L20)

  • P1-P99 G154 P1-P99 reference auxiliary coordinate (L20)

Q - Imaginary tool nose tip direction
R - Tool nose radius
*U - Incremental amount to be added to X-axis offset
*W - Incremental amount to be added to Z-axis offset
*X - X-axis offset
*Z - Z-axis offset

* indicates optional

Be aware: Many service and repair procedures should be done only by authorized personnel. The service technicians at your Haas Factory Outlet (HFO) have the training, experience, and are certified to do these tasks safely and correctly. You should not do machine repair or service procedures unless you are qualified and knowledgeable about the processes.

Danger: Some service procedures can be dangerous or life-threatening. DO NOT attempt a procedure that you do not completely understand. Contact your Haas Factory Outlet (HFO) and schedule a service technician visit if you have any doubts about doing a procedure.

Feedback