G01 Chamfering with A

Classic Control - Lathe Operator's Manual

The Online Interactive Operator's Manual is currently available in English only.

A PDF version of the Operator's Manual is available for download in multiple languages. Click the link below to view the Operator's Manual in your language. Click "Continue" to view the online version in English.

Get a translated PDF Download Continue

When specifying an angle (A), command motion in only one of the other axes (X or Z), the other axis is calculated based on the angle.

G01 Chamfering with A: [1] Feed, [2] Rapid, [3] Start Point, [4] Finish Point.

% o60012 (G01 CHAMFERING WITH 'A') ; (G54 X0 is at the center of rotation) ; (Z0 is on the face of the part) ; (T1 is an OD cutting tool) ; (BEGIN PREPARATION BLOCKS) ; T101 (Select tool and offset 1) ; G00 G18 G20 G40 G80 G99 (Safe startup) ; G50 S1000 (Limit spindle to 1000 RPM) ; G97 S500 M03 (CSS off, Spindle on CW) ; G00 G54 X4. Z0.1 (Rapid to clear position) ; M08 (Coolant on) ; X0 (Rapid to center of diameter) ; (BEGIN CUTTING BLOCKS) ; G01 Z0 F0.01 (Feed towards face) ; G01 X4. (position 3) ; X5. A150. (position 4) ; Z-2. (Feed to back of part) ; (BEGIN COMPLETION BLOCKS) ; G00 X6. M09 (Rapid Retract, Coolant off) ; G53 X0 (X home) ; G53 Z0 M05 (Z home, spindle off) ; M30 (End program) ; %
note: A -30 = A150; A -45 = A135

Be aware: Many service and repair procedures should be done only by authorized personnel. The service technicians at your Haas Factory Outlet (HFO) have the training, experience, and are certified to do these tasks safely and correctly. You should not do machine repair or service procedures unless you are qualified and knowledgeable about the processes.

Danger: Some service procedures can be dangerous or life-threatening. DO NOT attempt a procedure that you do not completely understand. Contact your Haas Factory Outlet (HFO) and schedule a service technician visit if you have any doubts about doing a procedure.

Feedback