Advanced Tool Management Introduction

Classic Control - Mill Operator's Manual

The Online Interactive Operator's Manual is currently available in English only.

A PDF version of the Operator's Manual is available for download in multiple languages. Click the link below to view the Operator's Manual in your language. Click "Continue" to view the online version in English.

Get a translated PDF Download Continue

Advanced Tool Management (ATM) lets you set up groups of duplicate tools for the same or a series of jobs.

ATM classifies duplicate or backup tools into specific groups. In your program, you specify a group of tools instead of a single tool. ATM tracks the tool use in each tool group and compares it to your defined limits. When a tool reaches a limit (e.g. number of times used, or tool load), the control considers it “expired.” The next time your program calls that tool group, the control chooses a non-expired tool from the group.

When a tool expires, the beacon flashes orange and the tool life screen automatically displays.

The ATM page is located in the Current Commands mode. Press CURRENT COMMANDS, and then PAGE UP until you see the ATM screen.

Advanced Tool Management Window: [1] Active window label, [2] Tool group window, [3] Allowed limits window, [4] Tool data window, [5] Help text

Tool Group - In the Tool Group Window the operator defines the tool groups used in the programs.

Previous – Highlighting and pressing ENTER changes the display to the previous group.

Next – Highlighting and pressing ENTER changes the display to next group.

Add – Highlight , enter a number between 1000 and 2999, and press ENTER to add a tool group.

Delete – Use or to scroll to the group to delete. Highlight and press ENTER. Confirm the deletion; answering Y completes the deletion; answering N cancels the deletion.

Rename - Highlight , enter a number 1000 and 2999 and press ENTER to renumber the group ID.

Search - To search for a group, highlight , enter a group number and press ENTER.

Group Id – Displays the group ID number.

Group Usage – Enter the order in which the tools in the group are called. Use the left and right cursor keys to select how the tools are used.

Description – Enter a descriptive name of the tool group.

Allowed Limits - The Allowed Limits window contains the user defined limits to determine when a tool is worn out. These variables affect every tool in the group. Leaving any variable set to zero causes them to be ignored.

Feed Time – Enter the total amount of time, in minutes, a tool is used in a feed.

Total Time – Enter the total time, in minutes, a tool is used.

Tool Usage – Enter the total times a tool is used (number of tool changes).

Holes – Enter the total number of holes a tool is allowed to drill.

Tool Load – Enter the maximum tool load (in percent) for the tools in the group.

TL Action* – Enter the automatic action to be taken when the maximum tool load percentage is reached. Use the left and right cursor keys to select the automatic action.

Tool Data

TL in Spindle – Tool in the spindle.

Tool – Used to add or remove a tool from a group. To add a tool press F4 until the Tool Data window is outlined. Use the cursor keys to highlight any of the areas under the Tool heading and enter a tool number. You can type zero clear the tool, or highlight the tool number and press ORIGIN to reset the H-Code, D-Code, and Flutes data to the default values.

EXP (Expire) – Used to manually obsolete a tool in the group. To obsolete a tool, press * (SHIFT, then 1). To remove an obsolete tool (indicated with an asterisk), press ENTER.

Life – The percentage of life left in a tool. This is calculated by the CNC control, using actual tool data and the limits the operator entered for the group.

CRNT PKT – The tool changer pocket that contains the highlighted tool.

H-Code (Tool Length) – You cannot edit the H-code unless Setting 15 is set to OFF. To change an H-code (if allowed), type a number and press ENTER. The number entered corresponds to the tool number in the tool offsets display.

D-Code (Tool Diameter) – To change a D-code, type a number and press ENTER.

note: By default, the H and D-codes in Advanced Tool Management are set to equal the tool number that is added to the group.

Flutes – The number of flutes on the tool. To edit this, type a new number and press ENTER. This is the same as the Flutes column listed on the tool offsets page.

Load – The maximum load, in percent, exerted on the tool.

Holes – The number of holes that the tool has drilled/ tapped/ bored using Group 9 canned cycles.

Highlight the Holes or Load field, and then press ORIGIN to clear their values. To change the values, highlight the value you want to change, type a new number, and press ENTER.

Feed Time – The amount of time, in minutes, that the tool has been in a feed.

Total Time – The total amount of time, in minutes, that the tool has been used.

Usage – The number of times the tool has been used.

Be aware: Many service and repair procedures should be done only by authorized personnel. The service technicians at your Haas Factory Outlet (HFO) have the training, experience, and are certified to do these tasks safely and correctly. You should not do machine repair or service procedures unless you are qualified and knowledgeable about the processes.

Danger: Some service procedures can be dangerous or life-threatening. DO NOT attempt a procedure that you do not completely understand. Contact your Haas Factory Outlet (HFO) and schedule a service technician visit if you have any doubts about doing a procedure.